FANUC系统铣床与加工中心工艺编程与操作实例.docx

1、FANUC系统铣床与加工中心工艺编程与操作实例单元二 外轮廓零件加工课题一 平面加工图211 平面加工任务图参考程序：O0001；G90 G94 G21 G17；G91 G28 Z0；G90 G54 M03 S350；G00 X-52.0 Y-50.0；Z5.0 M08；G01 Z-8.0 F50；Y50.0 F52；G00 Z5.0；X-44.0 Y-50.0；G01 Z-4.0 F50；Y50.0 F52；G00 Z5.0；X10. Y50.0；G01 Z-6.0 F50；G02 X10.0 Y-50.0 R50.0 F52；G00 Z20.0 M09；G91 G28 Z0；M30；课题二

2、 外形轮廓加工图221 零件加工任务图参考程序：（1）圆柱台加工程序0001；G90 G94 G40 G17 G21；G91 G28 Z0；G90 G54 M3 S350；G00 X62.0 Y0；Z5.0；G01 Z-4.0 F52；G41 D02 G01 X47.0 Y0 F52；G02 I-47.0 J0；G40 G01 X62.0 Y0；G41 D02 G01 X31.0 YO；G02 I-31.0 J0；G40 G01 X62.0 Y0；G41 D02 G01 X15.0 Y0；G02 I-15.0 J0；G40 G01 X62.0 Y0；G00 Z20.0；G91 G28 Z0；M

3、30；（2）外轮廓加工程序0002；G90 G94 G40 G17 G21；G91 G28 ZO；G90 G54 M03 S350；G00 X-62.0 Y52.0 M08；Z5.0；G01 Z-9.0 F52；G41 D02 G01 X-40.0 Y30.0 F52；G01 X-20.0 Y30.0；X30.0；G02 X40.0 Y20.0 R10.0；G01 Y-20.0；G02 X30.0 Y-30.0 R10.0；G01 X-30.0；G02 X-40.0 Y-20.0 R10.0；G01 Y10.0；G03 X-20.0 Y30.0 R20.0；G40 G01 X-62.0 Y52

4、.0；G00 Z20.0 M09；G91 G28 Z0；M30；粗加工时，选用20的立铣刀，刀具号为T02，刀具半径补偿号为D02，补偿值为10.2mm（0.2mm是精加工余量）。精加工时，选用12的立铣刀，刀具号为T03，刀具半径补偿号为D03，补偿值为6mm。单元三 内轮廓零件加工课题一 槽加工 图311 槽加工任务图参考程序：（1）十字槽粗加工程序0001；G90 G40 G21 G17 G94；G91 G28 Z0；G90 G54 M3 S480；G00 X30.0 Y0；Z5.0 M08；G01 Z-4.0 F40；X-30.0 F60；Z-8.0 F40；X30.0 F60；G00

5、 Z5.0；X0 Y25.0；G01 Z-4.0 F40；Y-25.0；Z-8.0 F40；Y25.0 F60；G00 Z5.0 M09；G91 G28 Z0；M30；（2）十字槽精加工程序0002；（主程序）G90 G40 G21 G94 G17；G91 G28 Z0；G90 G54 M3 S800；G00 X0 Y0；Z5.0 M08；G01 Z0 F40；M98 P0003 L02；G90 G00 Z5.0 M09；G91 G28 Z0；M30；0003；（子程序）G91 G01 Z-4.0 F40；G90 G41 D03 G01 X12.5 Y7.5 F50；G02 X7.5 Y12.

6、5 R5.0；G01 Y25.0；G03 X-7.5 R7.5；G01 Y12.5；G02 X-12.5 Y7.5 R5.0；G01 X-30.0；G03 Y-7.5 R7.5；G01 X-12.5；G02 X-7.5 Y-12.5 R5.0；G01 Y-25.0 ；G03 X7.5 R7.5；G01 Y-12.5；G02 X12.5 Y-7.5 R5.0；G01 X30.0；G03 Y7.5 R7.5；G01 X12.5；G02 X7.5 Y12.5 R5.0；G40 G01 X0 Y0；M99；课题二 型腔加工图331 型腔加工任务图参考程序：（1）型腔内粗加工程序0001；（主程序）G9

7、0 G40 G21 G94 G17；G91 G28 Z0；G90 G54 M3 S480；G00 X0 Y0；Z5.0 M08；G01 Z0 F50；M98 P0002 L02；G00 Z20.0 M09；G91 G28 Z0；M30；0002；（子程序）G91 G01 Z-4.0 F40；G90 G01 X7.0 Y0 F48；G03 I-7.0 J0；G01 X19.0 Y0；G03 I-19.0 J0；G01 X0 Y0 F100；M99；（2）型腔内轮廓精加工程序0003；（主程序）G90 G40 G21 G94 G17；G91 G28 Z0；G90 G54 M3 S480；G00 X

8、5.0 Y0；Z5.0 M08；G01 Z0 F80；M98 P0004 L02；G00 Z20.0 M09；G91 G28 Z0；M30；0004；（子程序）G91 G01 Z-4.0 F80；G90 G41 D01 G01 X20.0 Y-15.0 F48；G03 X35.0 Y0 R15.0；G01 Y6.7157；G03 X28.3333 Y16.1438 R10.0；G02 X16.1438 Y28.3333 R20.0；G03 X6.7157 Y35.0 R10.0；G01 X-6.7157；G03 X-16.1438 Y28.3333 R10.0；GO2 X-28.3333 Y1

9、6.1438 R20.0；G03 X-35.0 Y6.7157 R10.0；G01 Y-6.7157；G03 X-28.3333 Y-16.1438 R10.0；G02 X-16.1438 Y-28.3333 R20.0；G03 X-6.7157 Y-35.0 R10.0；G01 X6.7157；G03 X16.1438 Y-28.3333 R10.0；G02 X28.3333 Y-16.1438 R20.0；G03 X35.0 Y-6.7157 R10.0；G01 Y0；G03 X20.0 Y15.0 R15.0；G40 G01 X5.0 Y0；M99；单元四 孔加工课题一 钻孔、攻丝加工图

10、411 孔类零件加工任务图参考程序：0001；G91 G28 Z0；M06 T1；G90 G17 G49 G21 G94；G54 M3 S1200；G00 X20.0 Y100.0 M08；G43 H01 G00 Z50.0；G99 G81 X-15.0 Y65.0 Z-4.0 R5.0 F80；G98 X-30.0；G00 X-120.0；Y15.0；G99 G81 X-85.0 Y15.0 Z-4.0 R5.0 F80；G98 X-70.0；G91 G28 Z0 M09；M06 T02；G90 G49 G54 M3 S550；G00 X20.0 Y100.0 M08；G43 H02 G00

11、 Z50. ；G99 G73 X-15.0 Y65.0 Z-20.0 R5.0 Q2.0 F60；G98 X-30.0；G00 X-120.0；Y15.0；G99 G73 X-85.0 Y15.0 Z-20.0 R5.0 Q2.0 F60；G98 X-70.0；G91 G28 Z0 M09；M06 T03；G90 G49 G54 M3 S500；G00 X20.0 Y100.0 M08；G43 H03 G00 Z50. ；G98 G83 X-30.0 Y65.0 Z-21.0 R5.0 Q2.0 F60；G00 X-120.0；Y15.0；G98 G83 X-70.0 Y15.0 Z-21.0

12、 R5.0 Q2.0 F60；G91 G28 Z0 M09；M06 T04；G90 G49 G54 M3 S450；G00 X20.0 Y100.0 M08；G43 H04 G00 Z50. ；G98 G81 X-15.0 Y65.0 Z-21.0 R5.0 F50；G00 X-120.0；Y15.0；G98 G81 X-85.0 Y15.0 Z-21.0 R5.0 F50；G91 G28 Z0 M09；M06 T05；G90 G49 G54 M3 S350；G00 X20.0 Y100.0 M08；G43 H05 G00 Z50.0；G99 G82 X-15.0 Y65.0 Z-6.0 R5

13、.0 P2000 F60；G98 X-30.0；G00 X-120.0；Y15.0；G99 G82 X-85.0 Y15.0 Z-6.0 R5.0 P2000 F60；G98 X-70.0；G91 G28 Z0 M09；M06 T06；G90 G49 G54 M3 S50；G00 X20.0 Y100.0 M08；G43 H06 G00 Z50.0；G98 G85 X-30.0 Y65.0 Z-18.0 R5.0 F40；G00 X-120.0；Y15.0；G98 G85 X-70.0 Y15.0 Z-18.0 R5.0 F40；G91 G28 Z0 M09；M06 T07；G90 G49 G

14、54 M3 S100；G00 X20.0 Y100.0 M08；G43 H07 G00 Z50.0；G98 G84 X-15.0 Y65.0 Z-19.0 R5.0 F175；G00 X-120.0；Y15.0；G98 G84 X-85.0 Y15.0 Z-19.0 R5.0 F175；G91 G28 Z0 M09；M30；课题二 镗孔加工图421 零件加工任务图参考程序：0001；G91 G28 Z0；M06 TO1；G90 G94 G49 G17 G40 G21；G54 M03 S400；G43 H01 G00 Z50.0 M08；X-46.0 Y55.0；Z5.0；G01 Z-4.0 F

15、80；Y-55.0 F60；X46.0 F1000；Y55.0 F60；G41 D01 G01 X17.321 Y30.0 F60；X34.641 Y0；X17.321 Y-30.0；X-17.321；X-34.641 Y0；X-17.321 Y30.0 ；X-20.0；G40 G01 X65.0 Y55.0 F300；G91 G28 Z0 M09；M06 T03；G90 G54 G49 G40 M03 S1200；G43 H03 G00 Z50.0 M08；G98 G81 X0 Y0 Z-4.0 R5.0 F60；G91 G28 Z0 M09；M06 T04；G90 G54 G49 G40

16、M03 S500；G43 H04 G00 Z50.0 M08；G98 G81 X0 Y0 Z-20.0 R5.0 F60；G91 G28 Z0 M09；G28 X0 Y0；M06 T05；G90 G54 G49 G40 M03 S350；G43 H05 G00 Z50.0 M08；G98 G73 X0 Y0 Z-22.0 R5.0 Q2.0 F50；G91 G28 Z0 M09；G28 X0 Y0；M06 T06；G90 G54 G49 G40 M03 S250；G43 H06 G00 Z50.0 M08；G98 G73 X0 Y0 Z-25.0 R5.0 Q2.0 F45；G91 G28 Z

17、0 M09；G28 X0 Y0；M06 T07；G90 G54 G49 G40 M03 S200；G43 H07 G00 Z50.0 M08；G98 G73 X0 Y0 Z-26.0 R5.0 Q2.0 F40；G91 G28 Z0 M09；M06 T02；G90 G54 G49 G40 M03 S800；G43 H02 G00 Z50.0 M08；X46.0 Y55.0；Z5.0；G01 Z-4.0 F80；G41 D02 G01 X17.321 Y30.0 F60；X34.641 Y0；X17.321 Y-30.0；X-17.321；X-34.641 Y0；X-17.321 Y30.0；X

18、-20.0；G40 G01 X65.0 Y55.0 F300；G91 G28 Z0 M09；M06 T08；G90 G54 G49 G40 M03 S800；G43 H08 G00 Z60.0 M08；G98 G85 X0 Y0 Z-17.0 R5.0 F60；G91 G28 Z0 M09；M06 T09；G90 G54 G49 G40 M03 S1500；G43 H09 G00 Z60.0 M08；G98 G85 X0 Y0 Z-17.0 R5.0 F50；G91 G28 Z0 M09；G28 X0 Y0；M30；单元五 综合课题加工课题一 镜像加工 图511 加工任务图参考程序：0001；

19、（主程序）G90 G40 G21 G17 G94；G50.1 X0 Y0G91 G28 Z0；G90 G54 M3 S680；M08M98 P0002G51.1 X0M98 P0002G50.1 X0M09M300002；（子程序）G00 X-58.0 Y-48.0；Z50.0；Z5.0；G01 Z-3.0 F50；G41 D01 G01 X-47.0 Y-45.0 F100；X-47.0 Y-20.0；X-37.0 Y-20.0；G03 X-27.0 Y-10.0 R10.0；G01 X-27.0 Y10.0；G03 X-37.0 Y20.0 R10.0；G01 X-47.0 Y20.0；X

20、-47.0 Y42.5；X-28.0 Y42.5；G02 X-8.0 Y22.5 R20.0；G01 X-8.0 Y-20.0；X-30.5 Y-42.5；X-50.0 Y-42.5；G40 G01 X-58.0 Y-48.0；G00 Z50.0；M99；课题二 极坐标加工图521 加工任务图参考程序：0001；G54 G40；M08；G15；M03 S700；G00 X58.0 Y-10.0；Z50.0；Z5.0；G01 Z-5.0 F50；G41 D01 G16 G01 X36.0 Y-5.0 F100；G02 X24.0 Y-5.0 R6.；G03 X24.0 Y275.0 R-24.0

21、；G02 X36.0 Y275.0 R6.0；G02 X36.0 Y-5.0 R-36.0；G40 G15 G01 X58.0 Y-10.0；G00 Z150.0；M09；M30；课题三 旋转加工图531 加工任务图参考程序：0001；G54 G40；G69；M03 S700；G68 X0 Y0 R30.0；G00 X0 Y0；Z50.0 M08；Z5.0；G01 Z-5.0 F50；G41 D01 G01 X25.0 Y10.0 F100；G03 X15.0 Y20.0 R10.0；G01 X-15.0；G03 X-25.0 Y10.0 R10.0；G01 Y-10.0；G03 X-15.0

22、 Y-20.0 R10.0；G01 X15.0；G03 X25.0 Y-10.0 R10.0；G01 X25.0 Y10.0；G40 G01 X0 Y0；G00 Z150.0 M09；M30；课题四 综合零件的加工 图541 加工任务图参考程序：（1）正六边形加工程序0001；G90 G40 G21 G17 G94；G91 G28 Z0；G90 G54 M03 S400；G00 X0 Y55.0；Z5.0 M08；G01 Z-6. F60；G41 D01 G01 X0 Y29.0 F100；X10.97；G02 X19.63 Y24.0 R10.0；G01 X30.60 Y5.0；G02 Y-

23、5.0 R10.0；G01 X19.63 Y-24.0；G02 X10.97 Y-29.0 R10.0；G01 X-10.97；G02 X-19.63 Y-24.0 R10.0；G01 X-30.60 Y-5.0；G02 Y5.0 R10.0；G01 X-19.63 Y24.0；G02 X-10.97 Y29.0 R10.0；G01 X0；G40 G01 X0 Y55.0；G00 Z50.0 M09；G91 G28 Z0；M30；（2）斜六边形加工主程序0002；（主程序）G90 G40 G21 G17 G94 G69；G91 G28 Z0；G90 G68 X0 Y0 R10.0；M98 P0

24、003；G69；G91 G28 Z0；M30；0003；（子程序）G90 G54 M03 S400；G00 X0 Y40.0；Z5.0 M08；G01 Z-4. F60；G41 D01 G01 X0 Y25.0 F100；X10.97；G02 X16.17 Y22.0 R6.0；G01 X27.14 Y3.0；G02 Y-3.0 R6.0；G01 X16.17 Y-22.0；G02 X10.97 Y-25.0 R6.0；G01 X-10.97；G02 X-16.17 Y-22.0 R6.0；G01 X-27.14 Y-3.0；G02 Y3.0 R6.0；G01 X-16.17 Y22.0；G0

25、2 X-10.97 Y25.0 R6.0；G01 X0；G40 G01 X0 Y40.0；G00 Z50.0 M09；M99；（3）凹槽加工程序0004；（主程序）G90 G40 G21 G17 G94；G54 M03 S680；GO0 X60 Y-50；Z5.0 M08；M98 P0005；G51.1 X0 Y0 ；M98 P0005；G50.1 X0 Y0 ；G0 Z100.0 M09；M300005；（子程序）G00 X56.0 Y-46.0；G01 Z-8.0 F50；G41 D04 G01 X52.34 Y-33.55 F ；X34.88 Y-19.58；G3 X26.76 Y-29

26、.73 R6.5；G1 X41.94 Y-41.87；G40 G01 X56.0 Y-46.0；G00 Z5.0；M99；（4）孔加工程序0006；G91 G28 Z0；M06 T05；G90 G40 G21 G17 G94 G15；G54 M03 S1500；GO0 X0 Y0；G43 H05 G00 Z20.0；G16 G00 X40.0 Y40.0；G99 G81 Z-9.0 R5.0 F60；G00 X40.0 Y210.0；G98 G81 Z-9.0 R5.0 F60；G15；G91 G28 Z0；M06 T06；G90 G15 G54 M3 S500；GO0 X0 Y0；G43 H

27、06 G00 Z20.0；G16 G00 X40.0 Y40.0；G99 G81 Z-20.0 R5.0 F60；G00 X40.0 Y210.0；G98 G81 Z-20.0 R5.0 F60；G15；G91 G28 Z0；M06 T07；G90 G15 G54 M03 S450；GO0 X0 Y0；G43 H07 G00 Z20.0；G16 G00 X40.0 Y40.0；G99 G81 Z-20.0 R5.0 F50；G00 X40.0 Y210.0；G98 G81 Z-20.0 R5.0 F50；G15；G91 G28 Z0；M06 T08；G90 G15 G54 M03 S500；G

28、O0 X0 Y0；G43 H08 G00 Z20；G16 G00 X40.0 Y40.0；G99 G82 Z-10.0 R5.0 P2000 F60；G00 X40.0 Y210.0；G99 G82 Z-10.0 R5.0 P2000 F60；G15；G91 G28 Z0； M06 T09；G90 G15 G54 M03 S50；GO0 X0 Y0；G43 H09 G00 Z20.0；G16 G00 X40.0 Y40.0；G99 G85 Z-18.0 R5.0 F40；G00 X40.0 Y210.0 G98 G85 Z-18.0 R5.0 F40；G15；G91 G28 Z0；M30；数控

29、编程实例1根据图样要求、毛坯及前道工序加工情况，确定工艺方案及加工路线1）以已加工过的底面为定位基准，用通用台虎钳夹紧工件前后两侧面，台虎钳固定于铣床工作台上。2）工步顺序 铣刀先走两个圆轨迹，再用左刀具半径补偿加工5050四角倒圆的正方形。 每次切深为2，分二次加工完。2选择机床设备根据零件图样要求，选用经济型数控铣床即可达到要求。故选用XKN7125型数控立式铣床。3选择刀具现采用10的平底立铣刀，定义为T01，并把该刀具的直径输入刀具参数表中。4确定切削用量切削用量的具体数值应根据该机床性能、相关的手册并结合实际经验确定，详见加工程序。5确定工件坐标系和对刀点在XOY平面内确定以工件中心为工件原点，Z方向以工